快速铣面宏程序

k3684952

思路来自UG的面铣往复策略

O3001
G40 G17 G49 G80 G90
G91 G28 Z0.0

#1=160
#2=130
#3=63
#7=1
#8=1.6
#9=1
#17=2000.
#19=0.5

T#7
M06
G54G90
M3S1000
M8
(A-CHANG-#1)                  工件长度
(B-KUANG-#2)                  工件宽度
(C-DAOJU-ZHIJING-#3)          刀具直径
(D-DAOJUHAO-#7)               刀具号
(E-SHENDU-#8)                 需铣削的深度
(F-MEIDAOSHENDU-#9)           每刀深度
(Q-JINJI-#17)                 进给
(S-DAOJUZHIJINGBAIFENBI-#19)  刀具直径百分比

#11=-[#2/2]
G0G90X-[#1/2+#3/2+10.]Y-[#2/2]
G43Z100.H#7
Z[#8+5.]
IF[#9EQ0]THEN#9=#8
IF[#8LT#9]THEN#8=#9
IF[#8EQ0.4]GOTO5
#8=#8-#9
IF[#8EQ0]GOTO5

N1

G1Z#8F5000
N8
G1X[#1/2+5.]F#17
#11=#11+[#3*#19]
IF[#11GT#2/2]GOTO2
G1Y#11F#17
G1X-[#1/2+5.]F#17
#11=#11+[#3*#19]
IF[#11GT#2/2]GOTO3
G1Y#11F#17
GOTO8

N2
G1X[#1/2+#3/2+10.]F#17
G0Z[#8+5.]
G0G90X-[#1/2+#3/2+10.]Y-[#2/2]
#8=#8-#9
#11=-[#2/2]
IF[#8GT0.1]GOTO1
GOTO5

N3
G1X-[#1/2+#3/2+10.]F#17
G0Z[#8+5.]
G0G90X-[#1/2+#3/2+10.]Y-[#2/2]
#8=#8-#9
#11=-[#2/2]
IF[#8GT0.1]GOTO1

N5

G1Z0.1F5000
N10
G1X[#1/2+5.]F[#17/4]
#11=#11+[#3/2]
IF[#11GT#2/2]GOTO6
G1Y#11F#17
G1X-[#1/2+5.]F[#17/4]
#11=#11+[#3/2]
IF[#11GT#2/2]GOTO7
G1Y#11F#17
GOTO10

N6
G1X[#1/2+#3/2+10.]F[#17/4]
GOTO9

N7
G1X-[#1/2+#3/2+10.]F[#17/4]

N9
M5
M9
G91G28Z0.
M1


#1=160.
#2=130.
#3=63.
#7=2
#17=500

(A-CHANG-#1)
(B-KUANG-#2)
(C-DAOJU-ZHIJING-#3)
(D-DAOJUHAO-#7)
(Q-JINJI-#17)

T#7
M06
G54G90
M3S1000
M8

#11=-[#2/2]
G0G90X-[#1/2+#3/2+10.]Y-[#2/2]
G43Z100.H#7
Z[#8+5.]

G1Z0.F5000
N11G1X[#1/2+5.]F#17
#11=#11+[#3/2]
IF[#11GT#2/2]GOTO12
G1Y#11F#17
G1X-[#1/2+5.]F#17
#11=#11+[#3/2]
IF[#11GT#2/2]GOTO13
G1Y#11F#17
GOTO11

N12
G1X[#1/2+#3/2+10.]F#17
GOTO15

N13
G1X-[#1/2+#3/2+10.]F#17

N15
M5
M9
G91G28Z0.
M1
G91G28Y0.
M30
%

k3684952

#19=0.5表示刀具直径百分比为50%
程序含粗精加工，分两把刀具